---
title: "Countersink vs Counterbore: Angles, Callouts and When to Use Each"
description: "A countersink is a cone for a flat head screw; a counterbore is a flat pocket for a cap screw. Angles by standard, drawing symbols and sheet metal limits."
canonical: https://openspindle.com/blog/countersink-vs-counterbore
author: "Tom"
datePublished: 2026-11-12T17:00:00.000Z
dateModified: 2026-11-12T17:00:00.000Z
category: "Process & DFM"
---

# Countersink vs Counterbore: Angles, Callouts and When to Use Each

A countersink is a cone-shaped recess cut at the top of a hole so a flat head screw or rivet sits flush with the surface. A counterbore is a flat-bottomed, straight-walled pocket that recesses a socket head cap screw or bolt head below the surface. Match the countersink angle to the fastener: 82 degrees for inch flat heads, 90 degrees for metric, 100 degrees for most aerospace fasteners.

## Countersink and counterbore definitions

**Countersink (noun):** a conical recess at the mouth of a hole, cut to the same included angle as the underside of a flat head fastener so the head bears on the cone and finishes flush or slightly below the surface. **Countersinking (verb)** is cutting that cone, usually with a single or multi-flute countersink tool or a chamfer mill.

**Counterbore:** a cylindrical, flat-bottomed enlargement of a hole, larger than the fastener head and deep enough to swallow it. The head bears on the flat floor, not on a cone. Counterbores are cut with a piloted counterbore tool on a drill press, or more often on a CNC mill by helical or circular interpolation with an end mill.

A third, related feature is the **spotface**: a shallow counterbore that only cleans up a rough or sloped surface so a head or washer has a flat seat. It is called out the same way as a counterbore, with a small or unspecified depth.

The shapes are not interchangeable. A flat head screw in a counterbore has nothing to bear on except a thin ring at the hole edge. A socket head cap screw in a countersink touches the cone along its outer corner only and will not seat.

## Which one to use

Choose the fastener first; the fastener picks the feature.

**Use a countersink** when the surface has to be smooth and flush and the part is thin: covers, panels, hinge leaves, sliding surfaces, aerodynamic skins. Flat heads self-center in the cone, which helps line up two parts, but it also means the cone and the clearance hole must be concentric or the head will push the part sideways as it seats.

**Use a counterbore** when you need clamping strength and the part is thick enough to hide the head: fixtures, machine frames, tooling plates, structural brackets. A socket head cap screw bears on a flat floor and can take more clamp load than a flat head of the same thread size; flat head socket screws are generally rated for lower loads than cap screws, which the fastener standards note.

A few practical tiebreakers:

- If the material is thinner than the fastener head height plus a small land, a counterbore is not an option and a machined countersink may not be either. See the sheet metal section below.
- If two parts must be located precisely, do not rely on flat head self-centering across multiple screws. Tolerance stack between hole patterns makes some heads seat on one side of the cone. Use dowel pins for location and clearance-fit flat heads for clamping.
- If you need a flush surface and high clamp load, a low-head socket cap screw in a shallower counterbore is often a better compromise than a flat head.

## Countersink angles by fastener standard

The included angle of the countersink has to match the underside of the head. A mismatch concentrates the bearing load on the top or bottom edge of the cone, so the head can crack, the screw loosens as the edge yields, and the head does not finish flush.

| Fastener family | Included angle | Typical standards |
| --- | --- | --- |
| Inch flat head socket cap screws | 82 degrees | ASME B18.3 |
| Inch flat head machine screws (slotted, cross recessed) | 82 degrees | ASME B18.6.3 |
| Metric countersunk socket screws | 90 degrees | ISO 10642 |
| Metric countersunk machine screws (slotted, cross recessed) | 90 degrees | ISO 2009, ISO 7046 |
| Aerospace countersunk rivets and screws | 100 degrees | MS20426 rivets, NAS and MS screw series |
| Wood screws and some sheet metal screws | Usually 82 or 90 degrees by origin | Check the screw supplier |
| Machine center holes, deburring chamfers | 60 or 90 degrees | Not a fastener seat |

*An 82 degree inch screw in a 90 degree metric countersink bears only on its outer edge. If a drawing mixes inch and metric hardware, state the angle on every countersink callout.*

## How to call them out on a drawing

ASME Y14.5 defines symbols for both features, so the callout can sit in one line on a leader:

- **Countersink:** ⌵ followed by the countersink diameter at the surface and the included angle. Example for a #10 flat head socket screw: ⌀.221 THRU, ⌵ ⌀.42 X 82°.
- **Counterbore:** ⌴ followed by the counterbore diameter, then the depth symbol ↧ and depth. Example for a #10 socket head cap screw: ⌀.221 THRU, ⌴ ⌀.375 ↧ .200.
- **Spotface:** the counterbore symbol with SF inside it, or the counterbore symbol with a depth or remaining thickness.

Prefer dimensioning the countersink by its diameter at the surface rather than by depth. The diameter is what decides whether the head sits flush, it is easy to measure with a countersink gauge, and it does not change with tool tip geometry. If the head must sit below flush, say so with a diameter or a note such as HEAD FLUSH TO .005 BELOW.

In the CAD model, use the hole feature with the real countersink or counterbore rather than a sketched cut. A hole wizard feature carries its type into the STEP file as geometry a shop can read and measure, and it keeps the model consistent with the drawing callout. The [GD&T symbols reference](/reference/gdt-symbols-reference) covers the depth symbol and related notation, and the [countersink chart](/reference/countersink-chart) lists diameters and depths for common screw sizes.

## Countersinks in sheet metal

Sheet is where countersinks go wrong most often, because a standard flat head is tall relative to thin material. A #8 inch flat head is about 0.11 in tall; an M4 metric countersunk head is about 2.5 mm tall. Machine that cone into 1.5 mm sheet and the cone consumes the full thickness, leaving a knife edge with no straight bore under it.

A knife edge is weak: the head bears on a thin lip that deforms under preload, the screw loosens, and the hole can elongate under shear. A common aerospace rule of thumb is to machine countersink only when the sheet is thicker than the fastener head, and to dimple thinner sheet instead. For commercial parts, aim to leave a straight land of roughly a third of the sheet thickness below the cone as a starting point.

When the sheet is too thin to machine:

- **Formed (dimpled or coined) countersink.** A punch and die press the sheet itself into a cone, so the material bends rather than being removed. The back side gets a matching bump, which the mating part has to clear or receive. Many turret punches and press brake shops can form these with standard tooling for common screw sizes.
- **A thinner head.** Low-profile or 100 degree heads are shorter for the same thread.
- **Self-clinching flush hardware** or a different joint altogether; see [rivets vs rivet nuts vs self-clinching fasteners](/blog/rivets-vs-rivet-nuts-vs-pem-inserts).

Countersinks in sheet are a secondary operation. A laser or waterjet cuts the through hole; the cone is cut afterward on a drill press, mill or punch. Keep countersinks at least three thicknesses from edges and bends, as covered in [sheet metal DFM](/blog/sheet-metal-dfm), and remember that a cone cut before forming can distort if it sits close to a bend.

## Countersinks and counterbores in machined parts

On a CNC mill, both features are routine. The cost drivers are setups and tools, not the features themselves.

- **Side of the part.** A counterbore on the back face means a second setup if nothing else is cut from that side. Grouping countersinks and counterbores on faces that already need machining keeps them close to free.
- **Standard sizes.** A countersink sized for a standard screw is cut with a stock tool. A one-off diameter or angle may need a chamfer mill program or a special tool.
- **Depth and floor.** A counterbore floor is flat and the corner usually carries the end mill radius. If the head needs a sharp corner or a specific floor finish, say so; otherwise the shop picks a tool.
- **Thin walls.** A counterbore near an edge removes a lot of material; check the wall left between the counterbore and the part edge, especially in plastics.
- **Finish.** Anodize, plating and powder coat add thickness to the cone and floor. Powder coat in a countersink can stop a head seating flush, so mask or allow for it.

## What to put on the RFQ

For the quote, the shop needs to know the hole type, the fastener and how critical the seat is. A model with real hole features, plus a drawing that calls out the diameter, angle or depth, covers it. If you only send a STEP file, add a note such as: 6X COUNTERSINK FOR #10 FLAT HEAD SOCKET SCREW, 82°, HEAD FLUSH TO .010 BELOW, TOP FACE ONLY.

Tell the shop whether you are supplying the screws or want them supplied, and whether flushness is checked. A part that only needs the heads below a cover is cheaper to inspect than one where every head is measured for flush. If the part is sheet metal and you are not sure the gauge supports a machined countersink, say so and ask the matched shop to recommend dimpling or a different fastener.

## Related reading

- [Countersink chart](https://openspindle.com/reference/countersink-chart.md)
- [GD&T symbols reference](https://openspindle.com/reference/gdt-symbols-reference.md)
- [Drill size chart](https://openspindle.com/reference/drill-size-chart.md)
- [Sheet metal DFM](https://openspindle.com/blog/sheet-metal-dfm.md)
- [CNC machining](https://openspindle.com/capabilities/cnc-machining.md)
- [Sheet metal fabrication](https://openspindle.com/capabilities/sheet-metal-fabrication.md)

## Frequently asked questions

### What is a countersink?

A countersink is a cone-shaped recess at the top of a hole that lets a flat head screw or rivet sit flush with, or slightly below, the surface. Its included angle matches the underside of the fastener head: 82 degrees for inch flat heads, 90 degrees for metric, and 100 degrees for most aerospace fasteners.

### What is the difference between a countersink and a counterbore?

A countersink is conical and seats a flat head screw, whose tapered head bears on the cone. A counterbore is a straight-walled, flat-bottomed pocket that hides a socket head cap screw or bolt head below the surface. The head shape of the fastener decides which one to use.

### What angle is a countersink for a flat head screw?

It depends on the standard. Inch flat head screws to ASME B18.3 and B18.6.3 use 82 degrees. Metric countersunk screws to ISO 10642, ISO 2009 and ISO 7046 use 90 degrees. Aerospace countersunk rivets and many aerospace screws use 100 degrees. State the angle on the drawing.

### What are the countersink and counterbore symbols?

In ASME Y14.5, the countersink symbol is ⌵, written with the countersink diameter and included angle. The counterbore symbol is ⌴, written with the counterbore diameter, followed by the depth symbol ↧ and the depth. A spotface uses the counterbore symbol with SF inside it.

### Can you countersink thin sheet metal?

Only if enough material remains below the cone. A common aerospace rule of thumb is to machine countersink only when the sheet is thicker than the fastener head height. Thinner sheet is usually dimpled or coined, which forms the cone from the sheet itself, or redesigned with a lower head or different hardware.

### Should I dimension a countersink by diameter or depth?

By the diameter at the surface plus the included angle, in most cases. The surface diameter decides whether the head sits flush and can be checked with a countersink gauge. A depth dimension depends on tool tip geometry and is harder to measure.
