Process & DFM

What Is Kerf? Kerf Width by Cutting Process

Kerf is the width a cut takes away. Here is how wide it typically runs on every common cutting process, and the one thing not to do to your DXF because of it.

Tom PetriniCo-founder, OpenSpindle
Published 9 min read
KERF1/2 KERF OFFSETPART LINEYOUR DXF, FINAL SIZETOOLPATHOFFSET BY THE SHOPKERFMATERIAL REMOVEDHOLEDRAW AT FINAL SIZE. THE SHOP OFFSETS FOR KERF.

The short answer

Kerf is the width of material a cut removes. Typical kerf is about 0.1 to 0.3 mm on a fiber laser, 0.75 to 1.3 mm on an abrasive waterjet, 1 to 4 mm on plasma, and equal to the bit diameter on a CNC router. Kerf sets the narrowest slot and sharpest inside corner a process can cut. The shop offsets its cut path by half the kerf, so you should draw the part at final size and not offset your DXF.

Kerf in one sentence, and why buyers should care

Kerf is the width of material a cutting process removes as it cuts. A laser beam, an abrasive water stream, a plasma arc, a router bit, an EDM wire and a saw blade all have width, and everything inside that width turns into dust, slag, sludge or chips.

For a buyer, kerf matters in four places:

  • Part size. The cut path has to sit half a kerf outside the part line, or the part comes out undersize by a full kerf width.
  • Smallest features. A slot cannot be narrower than the kerf, and an inside corner cannot be sharper than the radius of the beam, stream or tool.
  • Fits. Tab-and-slot joints, press-fit holes and nested inlays have to account for how the edge is cut, including taper.
  • Material cost. On a crowded nest, the kerf between parts is material you pay for and throw away.

The good news is that you rarely have to calculate any of it. Handling kerf is the shop's job. Your job is to draw the part correctly and tell the shop which edges matter.

Typical kerf width by process

These are typical published ranges, not guarantees. Kerf on any given job depends on the machine, the power or amperage, the nozzle or tool, the material, the thickness and how worn the consumables are. A shop measures its own kerf with test cuts and sets the offset in its software.

ProcessTypical kerfMaterials and thicknessSet mainly by
Fiber laser0.1-0.3 mm (0.004-0.012 in) on sheet; 0.3-0.6 mm (0.012-0.024 in) on thick plateSteel, stainless, aluminum, brass, copper; thin sheet to about 25 mm plate on high-power machinesFocused spot size, focus position, thickness
CO2 laser0.15-0.4 mm (0.006-0.016 in)Acrylic, wood, plywood, paper, many plastics; thin metals on metal-cutting machinesLens focal length, material, thickness
Abrasive waterjet0.75-1.3 mm (0.030-0.050 in)Nearly any material: metals, stone, glass, composites, thick plateMixing (focusing) tube bore and wear
Pure waterjet (no abrasive)0.1-0.4 mm (0.004-0.016 in)Foam, rubber, gaskets, soft plastics, foodOrifice size
Air plasma (conventional)1.5-4 mm (0.06-0.16 in)Conductive metal, about 3 to 25 mm and upAmperage, nozzle, standoff
High-definition plasma1-3 mm (0.04-0.12 in)Conductive metal plate, about 3 to 40 mmAmperage, nozzle, gas
CNC routerEqual to the bit diameter, commonly 3.175, 6.35, 9.5 or 12.7 mm (1/8, 1/4, 3/8, 1/2 in)Wood, plywood, MDF, plastics, composites, aluminum sheetBit diameter, plus a little for runout
Wire EDMAbout 0.3-0.35 mm (0.012-0.014 in) with 0.25 mm wire; about 0.13-0.18 mm with 0.1 mm wireAny conductive metal, including hardened tool steel and carbideWire diameter plus the spark gap on each side
Band saw (for comparison)About 1-2 mm (0.04-0.08 in)Bar, tube, plate blanksBlade thickness and tooth set
Circular, cold or table saw (for comparison)About 2-4 mm (0.08-0.16 in)Bar stock, extrusion, wood panelsBlade plate and tooth width

Typical industry ranges compiled from machine and consumable manufacturer data and common shop practice. Your shop's measured kerf governs.

How kerf changes with thickness

Thermal processes widen as the material gets thicker, because the beam or arc has to stay hot and focused through more material and the operator opens up the focus and power to do it. Abrasive waterjet stays close to its tube bore at every thickness, but the bottom of the cut drifts as the stream slows down.

Mild steel thicknessFiber laserAbrasive waterjetHD plasmaAir plasma
1 mm (about 20 ga)0.1-0.15 mm0.8-1.0 mmNot a typical plasma jobNot a typical plasma job
3 mm (about 1/8 in)0.15-0.25 mm0.8-1.1 mm1.0-1.5 mm1.5-2.0 mm
6 mm (about 1/4 in)0.2-0.35 mm0.8-1.1 mm1.3-1.8 mm1.8-2.5 mm
12 mm (about 1/2 in)0.3-0.5 mm0.9-1.2 mm1.7-2.3 mm2.3-3.2 mm
25 mm (about 1 in)0.5-0.8 mm, high-power machines only0.9-1.3 mm at the top, with taper2.5-3.5 mm3.0-4.5 mm

Typical values for mild steel, for planning only. Stainless and aluminum differ, and every shop's numbers vary with its machine, amperage, nozzle and cut speed.

Kerf compensation: draw the part at its final size

This is the point that saves buyers the most grief. Draw the part at the size you want it to be, and do not offset your DXF to allow for kerf.

The shop's CAM software or the machine controller applies kerf compensation: it moves the cut path half a kerf outside every outer profile and half a kerf inside every hole and cutout. That way the edge of the kerf, not its centerline, lands on your part line. Shops tune that offset from test cuts and adjust it as nozzles, focusing tubes and lenses wear, which is why they want your nominal geometry and not a pre-compensated one.

If you offset the drawing yourself, the shop offsets it again. Outer profiles come out oversize and holes come out undersize, each by roughly a full kerf width. On a laser part that might be 0.2 mm, enough to make a bearing bore unusable. On a plasma or router part it can be 2 to 6 mm.

A clean cutting file looks like this:

  • Drawn at 1:1 in the units you state, with the units named on the RFQ
  • Closed contours, no overlapping or duplicate lines, no stray points
  • Part geometry only on the cut layer, with dimensions and notes on a separate layer or in a PDF
  • Fit clearances you want designed into the geometry (more on that below), but no kerf allowance

The one exception is when you run the machine yourself and know its kerf. When a shop cuts the part, leave compensation to them. If you are unsure what the shop expects, say "geometry drawn at nominal size, apply your kerf compensation" on the RFQ.

Kerf taper and bevel on waterjet and plasma

Kerf is not always a parallel-sided slot. On some processes the cut is wider at one face than the other, so the part edge is not square to the surface.

Waterjet taper. An abrasive stream loses energy as it goes deeper, so on a fast cut the kerf is wider at the top than at the bottom (a V-shaped taper), and on a very slow cut it can reverse. Typical taper ranges from a few hundredths of a millimeter to a few tenths per edge, growing with thickness and speed. Machines with dynamic taper-compensation heads tilt the nozzle to cancel most of it. If a waterjet edge has to be square, say so: the shop will slow down, use a compensating head, or quote a cleanup pass.

Plasma bevel. A plasma arc swirls, so one side of the cut comes out squarer than the other. Shops orient the cut so the good side lands on the part and the beveled side falls on the scrap. Conventional plasma typically leaves a few degrees of bevel. High-definition plasma is noticeably squarer. ISO 9013 classifies thermal-cut edges by perpendicularity and roughness, and calling out an ISO 9013 range is a precise way to state what edge quality you need.

Laser. Fiber and CO2 laser cuts are close to square on sheet. On thick plate there is some taper and striation toward the bottom of the cut, which matters mostly for precision fits and for cosmetic edges.

Router and wire EDM. The bit and the wire cut parallel walls, so taper is generally not a concern. Wire EDM can also cut deliberate tapers when you ask for them.

Smallest slot, hole, corner and web you can cut

Kerf sets the floor for small features. A process cannot cut a slot narrower than its kerf, and the inside corner radius it leaves is about half the kerf (for a router, the bit radius). Thermal processes add another limit: a web between two cuts that is too thin absorbs heat, warps or burns away.

ProcessTypical smallest hole or slotInside corner radiusTypical minimum web between cuts
Fiber laserAbout 1x material thickness in steel; smaller on thin sheetAbout half the kerf, near sharpAbout 1x material thickness
Abrasive waterjetAbout 1-1.5 mm in thin stock, must exceed the kerfAbout 0.4-0.6 mmAbout 1x thickness; thin webs can deflect in the stream
Air or HD plasmaAbout 1.5x thickness conventional; near 1x thickness with HD true-hole processesAbout 1-2 mmAbout 1.5-2x thickness
CNC routerThe bit diameterThe bit radius, so draw inside corners at or above itMaterial dependent; thin webs in MDF and particleboard break
Wire EDMAbout the kerf, 0.15-0.35 mm; internal features need a start holeWire radius plus spark gap, about 0.07-0.18 mmVery thin webs possible, since there is no cutting force and little heat distortion

Typical starting points. Small holes in thermal processes often come out tapered or out of round; if a hole has to hold a tight diameter, have it drilled or reamed and say so on the drawing.

Tab-and-slot fits: design in clearance, not kerf

Tab-and-slot parts are where kerf and design intent get confused. Kerf compensation makes the slot the size you drew. It does not make the tab fit. For that you need clearance, and clearance is a design decision you put in the geometry.

Three things to account for:

  • Sheet thickness tolerance. Sheet and plate are not exactly their nominal thickness. A nominal 3 mm sheet can run a tenth of a millimeter or more over, so size slots to the thickest material you might get, or ask the shop to measure the actual stock.
  • Process clearance. As a typical starting point, add about 0.1-0.25 mm of total clearance over the measured thickness for laser-cut slots, more for waterjet (taper narrows one face of the slot), and 0.5-1 mm or more for plasma.
  • Corners. A square tab will not seat fully in a slot with radiused inside corners. Add small relief notches or dog-bone cutouts at the slot corners, especially on waterjet, plasma and router parts.

If a fit is critical, cut a test pair before committing to a full run. A shop can tune a slot in minutes; changing a released design takes longer.

Kerf, nesting and what you pay for

Parts on a sheet are nested with a gap between them. That gap has to be at least one kerf wide, and thermal processes usually need more, often around one material thickness, so heat does not distort the neighbor and small parts do not tip up into the head.

Two levers move cost:

  • Common-line cutting. Straight-edged parts can share a single cut, removing one kerf and one pass per shared edge. It works best on rectangles and simple shapes and is a shop decision, but designing parts with matching straight edges makes it possible.
  • Material yield. A wide-kerf process on a crowded nest wastes more of the sheet. On expensive materials such as titanium, Inconel or thick copper, that waste shows up in the quote, and it is one reason waterjet and plasma prices are sensitive to how tightly parts nest.

Kerf also affects which process a shop picks for you. Fine features and tight fits push toward laser or wire EDM. Thick plate, heat-sensitive materials or stacked parts push toward waterjet. Heavy steel plate where a wider kerf and rougher edge are acceptable pushes toward plasma.

What to put on the RFQ

You do not need to specify kerf. You do need to tell the shop where kerf effects matter:

  • The material, temper and thickness, and whether the thickness is nominal or must be measured
  • That the geometry is drawn at nominal size and the shop should apply its own kerf compensation
  • Which edges or holes are critical, with tolerances, and which holes need drilling or reaming instead of cutting
  • Any edge requirement: square to the surface, a maximum taper or an ISO 9013 range, no dross, or cosmetic faces
  • Fit-critical pairs such as tab-and-slot or inlays, so the shop can cut a test fit first

Upload the DXF or STEP with a PDF that carries those notes at openspindle.com/quote. The matched shop picks the process that fits your features and sends one quote, usually in about 24 hours.

Sources

  • ISO 9013, Thermal cutting: classification of thermal cuts, geometrical product specification and quality tolerances
  • Laser, waterjet and plasma machine and consumable manufacturer cut charts (typical kerf and cut-quality data)
  • ASM Handbook, Volume 6: Welding, Brazing, and Soldering (thermal cutting processes)

Last reviewed by Tom Petrini

Let us quote your next part.

Upload your CAD or drawing and tell us your budget. We source it across our global network of partner shops and come back with your best-match quote, typically within about 24 hours.

  • Free quote in about 24 hours
  • No minimum order
  • No account needed to start
Add your CAD filesUp to 30 files per quote
Upload files & get a free quote

STEP · STL · IGES · DWG · DXF · SLDPRT · and more

No CAD file? Describe your project instead

Frequently asked questions

What is kerf?

Kerf is the width of material removed by a cut. Every cutting process has one: a laser beam, a waterjet stream, a plasma arc, a router bit, an EDM wire and a saw blade each turn a strip of material into waste as they cut. Typical kerf runs from about 0.1 mm on a fiber laser to several millimeters on plasma or a router.

How wide is laser cutting kerf?

Fiber laser kerf is typically about 0.1 to 0.3 mm (0.004 to 0.012 in) on sheet metal, widening to roughly 0.3 to 0.6 mm on thick plate. CO2 laser kerf in acrylic and wood is typically about 0.15 to 0.4 mm. The exact value depends on the machine, focus, material and thickness.

Do I need to account for kerf in my DXF?

No. Draw the part at its final nominal size. The shop's software applies kerf compensation, offsetting the cut path by half the kerf so the cut edge lands on your line. If you offset the file yourself, the shop offsets it again and the part comes out wrong by about a full kerf width.

What is kerf compensation?

Kerf compensation is an offset of the cutting path by half the kerf width: outward on outer profiles and inward on holes and cutouts. It is set in the CAM software or machine controller from the shop's measured kerf, and adjusted as consumables wear.

What is the kerf of a waterjet?

Abrasive waterjet kerf is typically about 0.75 to 1.3 mm (0.030 to 0.050 in), set mainly by the bore of the mixing tube, and it grows as the tube wears. The cut is usually slightly tapered, wider at the top on fast cuts. Pure waterjet without abrasive cuts a narrower kerf, about 0.1 to 0.4 mm, in soft materials.

How does kerf affect CNC router parts?

On a CNC router the kerf equals the bit diameter, commonly 1/8, 1/4, 3/8 or 1/2 in. That sets the narrowest slot and the smallest inside corner radius, which is the bit radius. Draw inside corners at or above that radius, or add dog-bone reliefs where a square part has to seat in the corner.